Unit 4: Grade 10 Technological Design - Robotics - Introduction to SolidWorks

Creo Start Screen

This unit will introduce you to SolidWorks, allow you to print your projects with our 3D printer, and create drawing files of your model. Being familiar with past sketching projects, 2D Draftsight, 3D Sketchup, the design process, orthographic views, dimensioning, and creating drawing files sets up students base knowledge and understanding of engineering standards and support to focus on more complex challenges.

Course Units and Descriptions
Unit Description
Review course outline for more details
1 Careers & Safety- Intro, computers, organization, and careers
2 Technical Sketching- freehand sketching, ortho, dimensions, ISO views, custom ortho design
3 Basic 2D & 3D CAD Intro- 2D coordinates, lines, ortho views, 3D drawing, and custom design digitized
4 3D Parametric Design- 2D sketch, 3D parts, feature tools, drawings, exporting for 3D printing
5 Sheet metal Design- thin material design, folds, assemblies, 2D print, project design, testing, and build
6 Robot Assembly- part reproduction, part assemblies, custom function design and build
7 Web Portfolio- Showcase course work, projects, and understanding with web portfolio and presentation

Unit Content Activity Quick Links, Click to Jump to Specific Activity!

  1. Unit 4, Act. 1: Creating a 3D Model Using SolidWorks
  2. Unit 4, Act. 2: Creating Orthographic Drawings
  3. Unit 4, Act. 3: Printing Your Model in 3D
SolidWorks Desktop Workspace

- TOP - Unit 4, Act. 1: Creating a 3D Model Using SolidWorks (SW) next

Situation:

Now that students have experienced and gained knowledge and skills on engineering communication n standards, methods, and process, looking at a "bigger tool box" with a lot more tools such as SolidWorks will allow for more opportunity to design very specific and detailed designs..

Problem/Challenge:

Students are to review and learn about SolidWorks and it's history. Using our familiar object, the step block, create the object in SolidWorks, then apply this process to to your custom key ring accessory that was designed earlier with the final ortho key ring accessory design. Two wiki pages - Expert Tools and Features and Design Log will be created with given templates and used to document, log, and share related information. Students will use the Expert Tools and Features wiki to research, present, and demonstrate a specific SolidWorks 2D Sketch or 3D Feature tool. The Design Log will be used by students to document and show their designs, process using SPICE and work accomplished.

Investigation

Investigation/Ideas:

Creating 3D model in SolidWorks with the step block should be straight forward using the steps, pictures, and instructions given. Students should be aware of key information as they go through this step block tutorial such as parametric driven, integrated 3D CAD/CAM/CAE solution, used by discrete manufacturers for mechanical engineering, design and manufacturing. With all of the previous experience with sketching, drawing views, selecting the front view, dimensioning, 2D drawing, and 3D introductory modeling, this should be easy to pick up the basics, as you are already familiar with the previous programs used. The tutorial in the next section will guide you step by step to support the creation of your customized key ring accessory.

Key Terms
layout
  • CAD- Computer Aided Designing is a technology concerned with creation, modification and optimization of a design - (SolidWorks, ProE, Catia, etc.) 
  • CAM- Computer Aided Machining is a technology which involves computer systems that involve, plan and control manufacturing process -  (SolidCam, MasterCam, HMS Works, etc.)
  • CAE- Computer Aided Engineering helps us to do the analysis of the CAD created product -  (Symulation, Ansys, Abaqus, etc.)
  • design intent - how your model behaves when dimensions are modified
  • parametric - features and relationships of the model, which is intended to capture the product’s behavior
  • constraints - component characteristics between two or more entities defining that component and/or property
  • relations - is a relation among the specification space and the description space, such that the related CAD-function is preserved
  • fully, over, and under defined - does your object drawn have the right amount of information needed by the program
  • best practices - are generally good drawing habits to keep organized, create less problems, and ease of work


Resource Links
Resource links

There are several resources on the web that can be helpful when familiarizing yourself with SW, a program of this caliber.



3D Key Ring Accessory Considerations
Attention

When creating your 3D model, there are several things you need to consider. Below is a reminder of the requirements and suggestions to keep in mind::

  • Have at least 4 mm of material everywhere for print plastic strength
  • Use a ruler if you are not sure physically how big your design will be
  • Key hole for key ring must be a minimum of 5 mm in diameter
  • Key hole must be placed in a practical location
  • Thickness of key ring accessory to be a minimum of 5 mm
  • Decide before which colour you would like to use for your project and buddy up with a group, so to minimize having to change the filament colour less
  • Scale it appropriately, so that it may fit into your pocket or purse easily
  • Should have a unique and custom look identifying you as the owner of it

Create/Construct:

Steps to take

Create a simple step block following the steps and support pictures below. As deceptively easy this assignment may be, by following the steps, keep in mind the underlining concepts in front view selection, 2D sketching, 3D modeling, dimensioning standards, and common sense reasons why the project is done they way it is with respect to Engineering standards and communications of ideas.

Steps and explanation breakdown:
  1. Start-up: Run SolidWorks application, and you will get an opening screen

  2. Solidworks Modeling

    Step 1
    Start-up

    Solidworks Modeling

    Step 2
    New Part

    Solidworks Modeling

    Step 3
    Model Workspace

    Solidworks Modeling

    Step 4
    Sketch / Plane

    Solidworks Modeling

    Step 5
    Front Selected


  3. New Part: Select new model part
  4. Model Workspace: Ensure you have ANSI standards and millimeters by selecting Options at the top, selecting Document Properties, and ANSI is selected as the drafting standard, then select Units and check that your document is in millimeters
  5. Sketch / Plane: Select the Sketch tab at the top to bring you into sketch mode and select your 2D sketching tool, in this case the line tool
  6. Front Selected: Select the plane you want to sketch on, in this case it is the front plane, the other two planes should disappear
  7. Front View: Select the View Orientation icon on the workspace near the top, and select the front view or use shortcut Ctrl +1 so you are looking straight at the front view. Another option is to right click on the front view and select the Normal To icon. it is always a good habit to sketch on a flat plane

  8. Solidworks Modeling

    Step 6
    Front View

    Solidworks Modeling

    Step 7
    Sketching

    Solidworks Modeling

    Step 8
    Snaps

    Solidworks Modeling

    Step 9
    Dimensions

    Solidworks Modeling

    Step 10
    Extruding


  9. Sketching: Starting at the x,y origin, start creating your object using direction snaps to keep lines straight and/or perpendicular your last line to draw the step block front outline
  10. Snaps: Above image shows the direction snaps in action, you will need to hover the mouse and then click one you have to snap show-up to draw the approximate shape, don't worry if it is not the exact right dimension, as they will be fixed later. The second last line segment use the snaps to align the last line starting point to line-up with the origin and close your shape. This is very important, make sure your object shape is closed with no openings or stray lines, otherwise the part can not be extruded later
  11. Dimensions: Once finished drawing your object, select Smart Dimension at the top above the sketch tab, and dimension your object being careful not to over define or under define, meaning putting the right amount of dimensions needed. Adding relations instead of dimensions in this process can be advantages, improve design intent, and less cluttered when possible
  12. Extruding: Once sketch is fully defined, meaning the drawing has the right amount of dimensions and relations, click the green check mark and select the Features tab. On the Features tab, you will be selecting the 3D feature you need to finish your object, and commonly this will be the Extruded Boss/Base, then drag or enter the desired depth and direction of your object
  13. Part Extruded: Once you have the right depth (Z axis distance) select the green check mark to complete. Note a yellowish extrusion does not show up, it is because there is something wrong with your shape, such as a stray line, object not closed, etc. which you will have to fix first before extruding

  14. Solidworks Modeling

    Step 11
    Part Extruded

    Solidworks Modeling

    Step 12
    Circle

    Solidworks Modeling

    Step 13
    Dimension Circle

    Solidworks Modeling

    Step 14
    Circle Location

    Solidworks Modeling

    Step 15
    Circle Hole Depth


  15. Circle: Next, you will need to make the hole by selecting the Sketch tab, then selecting the circle tool and clicking on the surface where you want to create the hole. It is not critical that it is located exactly, nor does it need to be drawn to exact size at this point
  16. step block
  17. Dimension Circle: Once circle is done, select the Smart Dimension button, and dimension the circle itself and confirm and enter the correct dimension
  18. Circle Location: Also dimension the circle location using the centre circle point and sides of object which should fully define that feature and you can click on the green check mark to finish
  19. Circle Hole Depth: Select the Features tab again and this time you will select Extruded Cut, which will remove material. In the properties manager change direction 1 to Up to Next for proper depth of hole removal, then click on the green check mark to complete feature

  20. Solidworks Modeling

    Step 16
    Hole Complete

    Solidworks Modeling

    Step 17
    Possible Edits

    Solidworks Modeling

    Step 18
    File Types Available


  21. Hole Complete: Once hole is complete turn your object to show the most detail for later showing in an ISO view. You could try just selecting the Orientation View icon above and selecting ISO view, but it may not be the best view
  22. Possible Edits: If you need to modify, change, or delete anything you have created, by right clicking on the feature or sketch item in the Feature Manager Design Tree, will give you those options. This is why it is a good practice to get into the habit to name your features in relation to model for later identifying what to edit
  23. File Types Available: There are several file types available, but you will save your tdj_stepblock_d-joe in five formats, its proprietary file format: SolidWorks Part Document (.SLDPRT), Free part viewer file Epart (.EPRT), Common CAD standard STereoLithography (.STL), picture file (.JPG) and lastly a portable file document (.PDF) format. It is important to add m for model at the end of your file for the .JPG and .PDF formats as they will conflict or overwrite later when you do the same with the drawing file
File Formats & Handing in Work
checkmark

There are several file formats that your work can be saved in. Your model work in SolidWorks has it's own proprietary or native extension unique to its part files. Here are examples of some of the most common file formats and naming conventions you commonly used:

  • SLDPRT - SolidWorks model part: tdj_stepblock_d-joe.sldprt
  • EPRT - Epart file allows users to view with a free Edrawings application:tdj_stepblock_d-joe.eprt
  • STL - Common CAD standard STereoLithography for use with Cura to convert file to print 3D: tdj_stepblock_d-joe.stl
  • JPG - Joint Photographic Experts Group: tdj_stepblock-mod_d-joe.jpg (note -mod or -m, as to not overwrite your drawing file later)
  • PDF - standard Portable File Document: tdj_stepblock-mod_d-joe.pdf (note -mod or -m, as to not overwrite your drawing file later)

For this project, hand in all these file formats in a folder using the file format nameing learned in class such as tdj_step-block_d-joe for example. Underscores separate sections of the file/folder name, dashes separate but keep the file name sections together.

Why the need for using a folder...
Tip

when working with 3D CAD programs, a model part is saved and then additional file types are also created based on that model part, those additional files saved, such as drawing files and assembly files not yet looked at, are directly dependent on that model file. By saving in the same folder, keeping model file names simple, short, and descriptive will allow all projects working seamlessly together. In a larger project with multiple model parts, assemblies, and drawing files, if the files are save in different locations, the dependent files remember where they are, so if moved will not open. If model parts are renamed after, dependant files will not open or function as they will not be able to find the origninal. Moral of this big tip, save all of your CAD related files in one folder and keep file names simple, short, and descriptive.

Your Key Ring Accessory Design

Once you have completed the step block, you now have a basic understanding of SolidWorks and can apply the same process to create your key ring accessory. Depending on your design you will have to try new feature tools and sketching techniques to build your design in SolidWorks. Working with and experimenting with planes, construction, center point, mid point lines, Further sketching tools such as trim/extend, offset, mirror, patterns, spline, arc, polygon, fillet, ellipse, text, etc may need to be used. Extruding a revolve and using features such as fillet, rib, shell, draft, sweep, loft, pattern, mirrors, etc may also need to be used. With many tools offered by SolidWorks, it is important not to get overwhelmed and patiently look at which individual tools will best help you draw/build your model. Use the resource links above and class demonstrations to further your knowledge and skills to completing your design. Thumbnails below show a gradual progression from a basic sketch to a finial finished key ring accessory.

Model Sample

Model Sample 1

Model Sample 2

Model Sample 2

Model Sample 4

Model Sample 4

Model Sample 5

Model Sample 5

Model Sample 7

Model Sample 7

moodleExpert and Design Wiki Pages

Create two wiki pages, one for 2D sketch and 3D feature tools and the other will be for a engineering design log.

wiki

The Expert wiki will be a place to show your selected 2D sketch or 3D feature tools. Students will show the name of the tool, a description about that tool/process, steps to use, sample image(s), and further support resource links.

The design wiki will be for your own designs, to document your project design process and progress with the first one bing the key ring accessory project.

Two templates have been provided below to use for wiki pages. To use the templates, you will need to click on the template link, then right click on the screen and select View Source Code, then copy the HTML code from between the two <body> and </body> to insert into your wiki file space

Evaluation:

Projects should be completed following steps and examples. Sketch dimensioning must be neat and organized. Ensure your final ISO saved view is always the best view shown and all five file types are saved in a folder using the naming convention learned at the beginning of the semester, example folder name: tdj_stepblock_d-joe. You are to continue your stepblock with a drawing in the next activity first then hand in both. Once successfully completed your stepblock model and drawing, you are to start on your Key Ring Accessory using the same process steps as your stepblock. Remember to use the checklist prior to handing in your work!.

Success
Evaluation Breakdown Component Descriptions Marks
Always double check that you have completed all components for full marks.
Step Block Model: completed, saved with best ISO view with the 5 file types 10
Key Ring Accessory Model: completed, saved with best ISO view with the 5 file types 20
Wiki Tool & Design Started: Both pages placed, header picture, and customized 10
Wiki Sketch or Feature: New tool/process name/description, steps, sample, and links 15
Demo Sketch or Feature: Rev wiki, demo - communication, knowledge, & understanding 15
Challenge

- TOP - Unit 4, Act. 2: Creating Orthographic Drawings next

Situation:

Having experienced some model creation with SolidWorks, will give you the opportunity to explore more of what SolidWorks has to offer.

Problem/Challenge:

Complete a drawing exercise on the step block model earlier created using the supplied template. Views must be place base on the three rules for the front view, which should already been taken into account when drawing the model. Scale and space for dimensions must be taken into consideration. Overall and detail dimensions must be placed appropriately considering spacing and locations. Shaded ISO and information block will also need to be completed. Using feedback from the instructor, make your key ring is done correctly following the same process as the step block..

Investigation/Ideas:

Investigation

Making drawings is important to do as it communicates a lot of information about your model, that would not normally be known from just looking at the model alone. Below shows thumbnail examples of a key ring accessory drawing :

DWG Sample 1

DWG Sample 1

DWG Sample 2

DWG Sample 2

DWG Sample 3

DWG Sample 3

DWG Sample 4

DWG Sample 4



Sample Ortho Drawing

The basics of making drawings are similiar in most CAD programs, the model file is used as a source for information to draw the views in drawing file. If something is changed in the model file the drawing will up date also based on the new changes.

Resorces

 

Create/Construct:

Creating Drawing

Below are the steps to create a basic drawing using SolidWorks. With Standard information blocks being quite bulky and a lot of unessessary information, a template fitting a standard letter landscape has been provided.

TioYou can copy the template file from the school pick-up folder and put into a folder on your USB or H drive under SolidWorks/Templates, then update SolidWorks in options under file locations add this location for custom templates.



  1. New Drawing: Open new drawing window, and select advance at the bottom

  2. Solidworks Drawing

    Step 1
    New Drawing

    Solidworks Drawing

    Step 2
    Template Selection

    Solidworks Drawing

    Step 3
    Multi Views

    Solidworks Drawing

    Step 4
    Views Loaded

    Solidworks Drawing

    Step 5
    Views Placed


  3. Template Selection: With the advanced window, select My Templates, and select the custom template a4-land-mf-cust-14e, should see a preview similar to above
  4. Multi Views: On the left, check off Create multiple views, then select the top, front, and right side views. Also in the More views, check off Current Model View - which should be the the best ISO view. Under Display Style, check off the hidden lines view style, then under Scale I have selected 2:1 as 1:1 is a little small, but later refined to 1.5:1 for a better fit. Once you have selected all of your options click on the green check mark to complete. On a side note here, when you first draw your object, it must be drawn keeping in mind the program will automatically use that to select views here. It may be possible to move to another plane, or change the plane, and change the default orientation view depending on your situation
  5. Views Loaded: You may want to re-adjust scale if needed
  6. Views Placed: Adjust view spacing and locations with equal spacing between the top, front, and side views
  7. Centre Lines: Select Annotation tab to get access to the centre line tool, and select to add centre lines to the appropriate views

  8. Solidworks Drawing

    Step 6
    Centre Lines

    Solidworks Drawing

    Step 7
    Dim Selections

    Solidworks Drawing

    Step 8
    Grid On

    Solidworks Drawing

    Step 9
    Dimensions

    Solidworks Drawing

    Step 10
    ISO Shading


  9. Dimension Selections: Note several specific dimensioning tools under the Smart Dimension button. Most situations the Smart Dimension will accommodate, but some situations, you may need to use a specific type of dimensioning tool
  10. Grid on: Before dimensioning your object views, turn the grid on by going into the Feature Tree, right click on sheet format 1 and select Display Grid, to use with dimension spacing
  11. Dimensions: Select Smart Dimension, and dimension overall and appropriate detail dimensions as needed in best locations, remember always dimension in the view that shows the detail the most
  12. ISO Shading: Note the ISO has been scaled a little smaller for better spacing, select ISO and in the left properties panel, change the Display Style to shaded with outline, then in the Annotation tab again, select the Note button to fill in the information block
  13. Note-No Leader: With the Note tool selected in the left properties panel, in the Leader window, select No Leader icon and note other options and changes that are possible here

  14. Solidworks Drawing

    Step 11
    Note-No Leader

    Solidworks Drawing

    Step 12
    Fill-in Info

    Solidworks Drawing

    Step 13
    Info Block Done

    Solidworks Drawing

    Step 14
    Saving

    Solidworks Drawing

    Step 15
    File Types


  15. Fill-in Information: When clicking in a location to make a note to type some text, note the long formating box that pops up with all the options you have. Fill in appropriate information such as you name, date, title, material, finish, drawing number, revision number, etc.
  16. Information Block Done: Note some fields in the information block fill in automatically
  17. Saving: Do not wait till the end to save your file, should be saving every few minutes with the Ctrl s, but at the end save your work
  18. File Types: Note all the different file types you can save to, although we will be concerned with the following file types - proprietary native drawing file (.SLDDRW), photo image (.jpg)
  19. Hand in the whole folder, with the folder properly named tdj-stepblock-d-joe, and all the files inside should have stepblock-d-joe from both the model and the drawing files. Keep in mind that the jpg of the model should have an -m and for the drawing version have a -d at the end, otherwise you will overwrite the model files when saving the drawing files as jpg
Creating Your Key Ring Accessory Drawing

After successfully creating the step block drawing exercise and feel you understand the process, get feedback from the instructor then start on your key ring accessory drawing. Ensure you have all your overall dimensions and the appropriate amount of detail dimensions, and that they are in the right locations. Any circular object features, use the centre lines to dimension with. To be also handed in with the drawing file and jpg

Evaluation:

You will be evaluated based on the completion of the above steps and your final product design. Remember when you hand in both your Step Block and your Key Ring Accessory projects to hand in only after you have completed and handed in the Solidworks Self/Peer Checklist sheet. This self/peer evaluation sheets is there to help you hand in the best product and get you written feedback on your completed work.

Eval
Evaluation Breakdown Component Descriptions Marks
Always double check that you have completed all components for full marks.
Ortho Step Block DWG - view placement, dimensions, info block, and file types 10
Ortho Key Fob DWG - view placement, dimensions, info block, and file types 20
Sample Key Ring Accessory

- TOP - Unit 4, Act. 3: Printing Model in 3D

Situation:

Having a 3D printer gives students the ability to see their design go from a virtual 3D version to a physical hand-held object. It is at this point that a lot of students will realize the power of what a designer has in Technological Design, and what Engineers experience when they see their design being built.

Problem/Challenge:

Take your STL file of your Key ring accessory and open it up with the Cura application, select best plane/direction your design must sit on the pad, to maximize printing quality. Explore tools and view options, then re-save your STL file as an AMF and a GCODE file and print your file using the Ultimaker 2. You are to add to your design log wiki showing your key ring accessory design process. While printing, you are to document/capture the print process by taking a starting print picture, halfway point picture and a finished picture of your key ring accessory and add to your individual design wiki along with pictures of your virtual SolidWorks model and drawing file/

Investigation/Ideas:

Investigation
Introduction to 3D Printing
filament colours

Printing in 3D is relatively new, last 10 years, and is now more common today to find a lot of hobbyist to have these in their home. The market is still expanding and new technologies, methods, and types of printers and print material is in constant flux. For this reason you can see a wide range of types and sizes out there. Ultimaker 2 is one printer that has been rated one of the best on the market for it size and use in a consumer environment.

3D Related Resources

Just like you learned how to sketch the step block either by additive or subtractive methods, you can see the similarities with 3D printing vs machining. Looking at the process of 3D printing, you can observe that this is a "additive technology" meaning when making/creating a part it adds material to build the part. The opposite is true with to today's machining process, which creates parts by taking material away and can be looked at as a "subtractive technology".



3D Printing Process

With the Ultimaker 2 3D printer, you will be able to print your design in 3D. It does this by melting plastic it draws from a roll through a plastic tube into a heating chamber that melts the plastic and the head is controlled by an x/y axis bars and servo motors which the printers controller runs based on the G-CODE of that object . Each layer is controlled by the Z axis, A little history and general information can be found here. Settings and maintenance can be found in the PDF Ultimaker2 User Manual.

3D BFB Printer

You will need save a copy of your part file (instructor checked design) as an STL file in SolidWorks. Using conversion software from Cura you will be able to build a AMF and GCODE print file from your exported standard STL file. It is important to place your digital object on the pad in Cura for best possible print. Both files are saved onto the SD flash card and then inserted into the Ultimaker 2 SD slot, The Ultimaker 2 glass base should be cleaned with a wet paper towel or similar, dry wiped clean, and then rub printing area with a glue stick to insure the plastic sticks to the glass base when printing. Here are some of the basic specs:

Price: ` $2500
Dimensions: 14.1 x 13.5 x 15.3 inches
Build volume: 9.1 x 8.9 x 8.1 inches
Filament: 2.85mm
Print speed: 30mm - 300mm/second
Software package: Cura
File types: STL/OBJ/DAE/AMF
Supports: Windows, Ubuntu Linux, Mac OS X
Connects with: USB, WiFi, SD card




Sample Pictures

Below are some pictures of our Ultimaker 2 printing in action with some recent prints.

Solidworks Modeling

Sample 1

Solidworks Modeling

Sample 2

Solidworks Modeling

Sample 3

Solidworks Modeling

Sample 4

Solidworks Modeling

Sample 5


Interesting 3D Printer FAQ's:
  • Can be used with any CAD program that has the ability to export .STL files
  • Supports several thermoplastic materials with two of the most common: PLA and ABS
  • PLA is the easiest material to work with and is considered a biodegradable thermoplastic that has been made from renewable resources such as corn starch and sugar cane. It is a preferred choice for support material, but will go brittle when exposed to sun and air in a short time, and is for this reason we will not normally be using it.
  • ABS is the second easiest material to work with and is an engineering polymer commonly used to produce car bumpers due to its toughness and strength. It does however have a tendency to warp on larger geometries but is very stable in not going brittle like PLA
  • Support material is used to make scaffolding in low resolution to support the geometry of a model which otherwise would be printed in mid-air, can be removed by simply breaking it away/off of your printed part and then sanding or filing to finish off.
  • Finish surface quality depends on the geometry and layer thickness you are printing. For example the 0.125mm layer thickness will result in a smoother surface compared with the 0.25mm layer thickness, however it will take longer to print.

3D Key Ring Accessory Considerations and Possible Refinements
Attention

When creating your 3D model, there are several things you need to keep in mind. At this point your sketch is done and you may need to do some more refinement in your model. Below is a reminder of the requirements and suggestions to keep in mind::

  • Have at least 4 mm of material everywhere for print plastic strength
  • Use a ruler if you are not sure physically how big your design will be
  • Key hole for key ring must be a minimum of 5 mm in diameter
  • Key hole support material must be a minimum of 5 mm
  • Key hole must be placed in a practical location
  • Thickness of key ring accessory to be a minimum of 5 mm
  • Decide before which colour you would like to use for your project and buddy up with a group, so to minimize having to change the filament colour less
  • Scale it appropriately, so that it may fit into your pocket or purse easily
  • Should have a unique and custom look identifying you as the owner of it
  • Use rounds to reduce sharp edges for safety and pocket wear

Create/Construct:


3D Drawing Steps

You will need your STL file from your key ring accessory prior to creating the GCODE file using Cura. :Use the following steps to print your 3D key ring accessory:

  1. Select Ultimaker 2: Start the Cura application. If this is the first time running it you will see a configuration wizard window. Select Ultimaker 2 and click Next

  2. Solidworks Modeling

    Step 1
    Select Ultimaker 2

    Solidworks Modeling

    Step 2
    Firmware Ignore

    Solidworks Modeling

    Step 3
    Opening Screen

    Solidworks Modeling

    Step 4
    STL File Loaded

    Solidworks Modeling

    Step 5
    Layer View 1


  3. Firmware Ignore: Next screen will suggest you update the firmware, which is base code for the Ultimaker 2's control system. Just bypass this by selecting Finish
  4. Opening Screen: This will show you the current version and have their 3D logo on the pad. You will need to clear this object by selecting File, then Clear Platform
  5. STL File Loaded: Click on File menu, and select Load Model File, and use the window to select and load your STL model part. At this stage you may need to rotate clicking the rotate tool icon in the lower left corner, which will activate the X, Y, and Z rotate circles. Just drag your object to rotate to a better print setting, for example the step block hole is better printed with the centre perpendicular to the platform
  6. Layer View 1: Make sure the Platform Adhesion button is set to none. Brim means it will print a support base raft which is not normally needed and you will later have to remove it making more work for you. Explore the different print views you can do with the Print Viewer icon in the top right corner
  7. Layer Build View: This shows an example of halfway through the print and if you look closely you will see the web framed internal design

  8. Solidworks Modeling

    Step 6
    Layer Build View

    Solidworks Modeling

    Step 7
    Save G-Code

    Solidworks Modeling

    Step 8
    File Name Ex.

    Solidworks Modeling

    Step 9
    Save AMF

    Solidworks Modeling

    Step 10
    Control Panel


  9. Save G-Code: Saving the GCODE is what the Ultimaker 2 will use to print your object
  10. File Name Ex.: This shows the Save Tool path window and file name convention - stepblock-d-joe.gcode
  11. Save AMF: This screen shows the Save 3D Model window, which allows you to save your STL file as an AMF file format for later opening with all recent settings saved.
  12. Control Panel: Rotary dial is used to select Print, then you rotate to find your GCODE file which will show the print time and amount of filament plastic will be used, press the rotary button to start print. Heated glass platform should be cleaned using a little bit of water and paper towel, then dry and put some glue down from glue stick to ensure print sticks to the platform
  13. Printing Started: After starting the print, the print head heats up for about a minute, then will start printing

  14. Solidworks Modeling

    Step 11
    Printing Started

    Solidworks Modeling

    Step 12
    First Layer

    Solidworks Modeling

    Step 13
    Half Way

    Solidworks Modeling

    Step 14
    Inside support

    Solidworks Modeling

    Step 15
    Print Finished

    Remember to take some pictures of the 3D printing process to use in your design wiki page.


  15. First Layer: Close-up of first layer being printed
  16. key fob
  17. Half Way: Note you can see the glue on the glass and the small print head with a servo motor to the left which drives the track/rails
  18. Inside support: Part way though the print you can see the web frame structure inside the object print, i.e. objects are not printed with solid plastic as this would take a lot longer and use more material
  19. Print Finished: You will need to use a thin scrapper to work object off of glass platform once it has had a chance to cool down

Evaluation:

You need to make sure you have followed all steps through this process. You will need to clean up your printed object using a file and/or sandpaper. Evaluation is based on your process and final design handed in, in the appropriate files and formats.

You will be evaluated based on the completion of the above 10 steps and your final product design.

Evaluation Breakdown Component Descriptions Marks
Always double check that you have completed all components for full marks.
Key Ring Accessory - successfully 3D printed 10
Design Log - Key Ring Acc. SPICE design process shown with pictures and progress 20